Anaheim DPJ72LC2, DPJ72LC3, DPJ72LC4 manual System Programming

Section 4 System Programming 57

The first tool used in the program is tool #1, so it is selected in the Current Tool pull-down menu on the main screen. The tool change position is defined as Machine Coordinates X=2, Y=2, Z=0. Tool #1 is loaded in the machine tool. Program zero has been set using tool #1. Program zero is set at Machine Coordinates X=0, Y=0, Z=-4. The machine tool is moved to Program Coordinates X=0, Y=0, Z=1 before the G-Code file is run.

G00	Z.25	Move the Z axis down to Program
		Coordinates X=0, Y=0, Z=0.25, Machine
		Coordinates X=0, Y=0, Z=-3.75
G01	Z-1.0 F10	Move the Z axis down to Program
		Coordinates X=0, Y=0, Z=-1, Machine
		Coordinates X=0, Y=0, Z=-5
G00	Z.25	Move the Z axis up to Program Coordinates
		X=0, Y=0, Z=0.25, Machine Coordinates
		X=0, Y=0, Z=-3.75
G28		Move the Z axis up and the X and Y axes
		across to the Tool Change Position, Program
		Coordinates X=2, Y=2, Z=4, Machine
		Coordinates X=2, Y=2, Z=0
M06 T2		Change the tool to Tool #2. All coordinates
		remain unchanged.
G43	H2	Apply the tool length compensation for tool
		#2. The offset amount is 0.750 (2.250-
		1.500). The tool does not move. However,
		the Program Coordinates change to X=2,
		Y=2, Z=3.25. The Machine Coordinates
		remain unchanged at X=2, Y=2, Z=0.
G29	X1 Y1 Z0.25	Move the X and Y axes across and the Z
		axis down to Program Coordinates X=1,
		Y=1, Z=0.25, Machine Coordinates X=1,
		Y=1, Z=-3.0
G01	X3 Y3 Z-1 F20	Linear interpolation to Program Coordinates
		X=3, Y=3, Z=-1, Machine Coordinates X=3,
		Y=3, Z=-4.25
G28	Z0	Rapid move in the Z axis only to Program
		Coordinates X=3, Y=3, Z=3.25, Machine
		Coordinates X=3, Y=3, Z=0
M06 T3		Change the tool to tool #3. All coordinates
		remain unchanged.
G43	H3	Apply the tool length compensation for tool
		#3. The offset amount is –1.250 (1.000-

2.250). The tool does not move. However, the Program Coordinates change to X=3,